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# Tutorial - Modeling 3 pipe joint in SolidWorks?

By Sudhir Gill on 12 Mar 02:41 3 answers 3968 views 6 comments

Tutorial on Modeling 3 pipe joint in SolidWorks.

### 3 answers

• over 1 year ago

Here is the tutorial.

1. ### Step 1

Start SolidWorks.

2. ### Step 2

Top plane >> Sketch.

3. ### Step 3

Draw three equal construction line at 120º.

4. ### Step 4

Exit the sketch.

5. ### Step 5

Reference geometry >> Plane. Select the line and the end point. Click OK.

6. ### Step 6

Similarily create another plane for the line.

7. ### Step 7

Same step for third.

8. ### Step 8

Plane1 >> Sketch.

9. ### Step 9

Draw a circle of 50mm dia.

10. ### Step 10

Select Extruded surface under surface tab.

11. ### Step 11

Extrude it towards the Origin with a distance of 100mm.

12. ### Step 12

Plane2 >> Sketch.

13. ### Step 13

Draw circle of 50mm diameter.

14. ### Step 14

Extrude surface it with the same distance and towards the origin.

15. ### Step 15

Plane3 >> Sketch.

16. ### Step 16

Draw circle of 50mm diameter.

17. ### Step 17

Extrude surface it with the same distance and towards the origin.

18. ### Step 18

Top plane >> Sketch.

19. ### Step 19

Draw 3 lines collinear to each other and parallel to edge of pipe. These are 3 lines not one. This will create 3 edges.

20. ### Step 20

Exit the sketch and select trim surface under surfaces tab.

21. ### Step 21

Trim the surface using the line sketch as trimming tool.

22. ### Step 22

Similarily trim other two extrusions.

23. ### Step 23

Select lofted surface tool under surfaces tab.

24. ### Step 24

Select the edge of the pipe.

25. ### Step 25

And the corresponding edge of the other pipe.

26. ### Step 26

Under start/End constraints change them to Tangency to face. Click OK.

27. ### Step 27

Create the same feature for other two pipes.

28. ### Step 28

Same step for remaining two edges.

29. ### Step 29

Select Filled surface tool under surfaces tab.

30. ### Step 30

Select all upper the edges of the pipes.

31. ### Step 31

Change contact to tangent.

32. ### Step 32

Enable Apply to all edges. Click OK.

33. ### Step 33

Repeat the same step for lower side.

34. ### Step 34

Knit surface under surfaces tab.

35. ### Step 35

Select all surfaces and enable merge entities. Click OK.

36. ### Step 36

Now all surfaces are knitted into one.

37. ### Step 37

Select Thicken tool under surfaces tab.

38. ### Step 38

Select the surface knit and thickness be 2mm outside direction. Click OK.

39. ### Step 39

And the 3-pipe joint is created.

• over 1 year ago

very nice man!

• 12 months ago

Hy,
Thanks for your help but how did you select only a part of the edge (Step24)
Regards