CAN ANYONE TELL ME HOW TO WRITE TEXT IN CATIA ON ANY OBJECT OR PRODUCT
I AM ADDING A RENDERING WHICH I HAVE DOWNLOADED FROM GRABCAD....CAN ANYONE TELL ME HOW WE CAN WRITE SOME TEXT IN CATIA ON AN OBJECT.....IN THIS CASE THE OWNER HAS WRITTEN GRABCAD,,,,,
I think I understand what you mean: you want to write words as decals on a surface? There is more than 1 way to do it, here's mine (it's rather long, but not too complicated):
The easiest way is if you already have a picture of the text you want (In my case, I wanted to write US AIR FORCE on my airplane: North American XB-70 Valkyrie. You can download the CATpart if you want to see, although it is a bit heavy.)
My method works by projecting lines onto the surface where you want the words to go. THIS DOES NOT WORK FOR SOLIDS, THIS IS FOR SPLITTING SURFACES. You have to be in the Generative Shape Design (NOT Part Design) of CATIA to do this. I will use the photo you uploaded to guide you in this example.
1. You have to have a .jpg picture of the letters GRABCAD in the style you want.
2. You have to create a plane in the CAT part of the aircraft. This is the plane from which you will project your lines onto the surface of the aircraft. You have to create the plane so that when you look at the aircraft from this plane, the letters look exactly the same as your picture. In this example, you should create a plane that is "on the left" of the aircraft (see picture 1).
3. Create a sketch on the plane you just made. In here you will have to insert the picture of the letters, either by copy/pasting, or by inserting Object, I don't remember quite how. If you can't insert the picture it will just be more difficult. (picture 2)
4. In this sketch is where you create whatever text you want using lines. If you have managed to insert the .jpg into the sketch, then all you have to do is trace the letters. You can also draw or make any sort of decals. Always remember that while you are drawing on this plane, your text has to "fit inside" the shape of the aircraft. If it does not, you project part of your text onto empty air (picture 3).
5. After you have made your text, you now have the text stuck on the plane. You now have to project it onto the surface.
6. In Generative Shape Design (GSD) there is a command called Multiple Extract. THIS IS A VERY USEFUL AND POWERFUL TOOL, useful for extracting particular geometries out of operations. Once you click on it, you choose ALL the lines that represent your letters in the sketch. You know have a Multiple extract that has all your letters.
7. There is another command in GSD called Project. In this you choose what you project (the Multiple Extract you just made), where you project it (the surface on the aircraft) and in what direction (choose the plane where the sketch was made). If all goes well, the letters are projected onto the surface.
8. Finally, you have to split the surface you have just projected the lines onto. Now here is the tricky part. All your letters have to be CLOSED "loops" on the aircraft surface, or you wont be able to split the aircraft surface. You will notice that the "G" in GRABCAD has 3 surfaces, or three closed "loops". For this, you have to choose extract again, and then select all the projected lines that form a closed loop for ONLY ONE LETTER.
9.There is a command in GSD that is called Split Surface. You choose the surface first, and then the multiple extract you made from the projected lines for only one letter. You also have to choose "keep both sides". Your surface should be split. You now have a surface that represents the shape of one letter on the surface of your aircraft. Do the same for all the other letters, and you will have your text on the aircraft surface. You can give it any color you want, and give it different textures too.
You will notice that this is a slow method, but it also lets you learn how to handle some very powerful tools in CATIA. If you practice, you will learn a lot.
You have to save the file as a DXF, close out the CATdrawing and open the DFX inside of catia. Then you can highlight the text inside the DXF file and paste them into sketches. Let me know if that gets the job done.
1. Open Drawing File
2. Use text editor to type what you want, make it the desired size and font
3. Save file as, DXF, not CATdrawing
4. Open DXF inside of CATIA, you can now see your text is an outlined sketch.
5. Drag select the text
6. Right Click text and copy
7. Open up sketch workbench, and paste