20 answers

• 
  Aykut Dana about 1 year ago

  Cylinders - 2

  1. Step 1

     open a sketch on front plane and draw water canal profile

     

  2. Step 2

     extrude it

     

  3. Step 3

     create a plane bottom of body and use mirror command for to mirror water canal

     

  4. Step 4

     after open a sketch on this surface

     

  5. Step 5

     draw a sketch like this and use cut extrude command

     

  6. Step 6

     go to left side, open a sketch and draw a sketch like this

     

  7. Step 7

     extrude it. please attention that to make direction 'up to surface'. select the outer surface of the cylinder

     

  8. Step 8

     open a sketch on same surface and draw semi-circular profile. it have to be closed profile

     

  9. Step 9

     create the plane 3 ( it is at the center of water canal) then draw the path.( we will use sweep command)

     

  10. Step 10

      use sweep command. then mirror it

      

  11. Step 11

      create a inlet part like this

      

  12. Step 12

      close the back side with your method

      

  13. Step 13

      mirror all things and your water cooled 12 cylinders are ready

      

  1. 
     kandarp 9 months ago

     i last step you can not directly do mirror...
     u should copy body for 90 degree + 17mm increment in z direction....

  2. 
     venkatesh 9 months ago

     thank u.....it is very useful.......

  3. 
     Armenio Gabrentina 9 months ago

     thank you once more...I've follow it

• 
  Aykut Dana about 1 year ago

  use bodies to mirror option select the bodies and uncheck the ''merge solids'' box

• 
  RYAN about 1 year ago

  i hate free hand on snip lol but check this box

• 
  Phil Kight 9 months ago

  For kandarp, here is the picture of the cylinder cuts for the sleeve. What I've done is to go back to before the water sleeve is added and redrawn the 100 and 110 mm circles. That is the profile that we need to extrude after the water canal has been added.

  1. Step 1

     Here is the picture of a single cylinder before the linear command and water canal has been applied. I've done this to show where the profile for cutting the water canal comes from.

     

  2. Step 2

     Here we can see that the water canal is bisecting the gap around the sleeve. We need to remove that, by opening a drawing on the face of the cylinder. Then drawing the circles that we can trim to use as templates for the cut extrude. One @ 100mm and one @ 110, and two circles at 24mm tangent to the smaller circle. 22.707 mm from the center (left or right) of the two circles, and 57.692 mm up.

     

  3. Step 3

     Here I've drawn the 4 circles needed for the extrusion, before the trim has been applied.

     

  4. Step 4

     Here is what it should look like after the trim has been applied.

     

  5. Step 5

     and here is the sleeve with the extruded cut. Hope this helps you out.

     

  1. 
     kandarp 9 months ago

     thanx for the answer...

  2. 
     Kong 6 months ago

     I found a easier way is to click on the area where you want to create these curves. The area will be highlighted and you just click "convert entities" button in the sketch menu and the curves are then generated. Let me know if this is not correct.

  3. 
     kandarp 9 months ago

     in last step you can not directly do mirror...
     u should copy body for 90 degree + 17mm increment in z direction....

     is it true?

• 
  jan stam 11 months ago

  Could you please highlight step 4 a bit more, its too vague for me to see what you're actually trying to accomplish. thank you for tutorial though, it's really nice

  1. 
     Leo Kiviluoma 10 months ago

     Same here. I skipped step 4. So my engine is a bit heavier but I'll hope it is more resistant :))

  2. 
     Phil Kight 9 months ago

     after a bunch of trial and error, I figured out what is he is trying to accomplish. The bottom of the cylinder sleeve needs to be fully rounded, to the points of the intersection between the sleeves. I'll post a picture below for you.

  3. 
     adam 10 months ago

     I am having the same problem. Its very unclear what he is trying to cut there.

  4. 
     Christos Georgoulas 10 months ago

     me too

• 
  Phil Kight 9 months ago

  Here is what I've come up with for the cylinder cuts, around the sleeves. I've also noticed that the water jacket is incomplete, for it to be accurate, there would need to be in inlet, as well as outlet for each water tube. Hopefully you'll be able to open the drawing, or else I'll have to figure out how to post pictures here.

  Attachments

  Cylinder_Head_with_water_canal.SLDPRT, 1.62 MB
  Download

  1. 
     kandarp 9 months ago

     can u uplod .igs or .stp file?

  2. 
     Phil Kight 9 months ago

     I did not see either of those options when saving a snip. What about .png?

  3. 
     kandarp 9 months ago

     i m working with creo 1.0
     so up load any formet which respond in it.....!!!!

  4. 
     kandarp 9 months ago

     in last step you can not directly do mirror...
     u should copy body for 90 degree + 17mm increment in z direction....?

  5. 
     kandarp 9 months ago

     i m able to open .CATpart file..

• 
  Phil Kight 9 months ago

  Here is how I made the 3rd plane.

  1. Step 1

     first choose the 1st plane at the 35 degree angle, as the reference point for the plane insertion. Insert the new plane perpendicular to plane one, next click in the box for a second reference, use any point on the side where you want to insert the plane, and then click in the 3rd box reference point. Here you need to click on a point in the same plane as the second reference point. I've circled the two points I choose for the second plane in this snip. It's in .jpg format so hopefully you'll be able to see what I've done.

     

• 
  Deepak Rajendran 4 months ago

  instead of steps 8,9 and 10 v can use the revolve command for 180 degree...i have attached the image of that sketch to be revolved........

  Added images

  

• 
  kandarp 10 months ago

  in your water chanal so many punchurs r there.......!!!!!!!!1

  1. 
     Phil Kight 9 months ago

     can you rephrase the question. I'm not sure I'm understanding what your asking.

  2. 
     kandarp 9 months ago

     " U " section of lag 15mm make some blank space between chanal & cylinder surface.....(view fron bottom of cylinder)

     so i use " C " section of same dimention & sweep it at all around 6 cylinders & in other step extrud rectangle of " c " section's flat surface & extrude up to next surface...(as step 7).....

  3. 
     kandarp 9 months ago

     this method will eliminate step 5....!!

  4. 
     Phil Kight 9 months ago

     step 5 is removing the material from the extrude of the water canal to the cylinder sleeve. Your method is a good idea.

  5. 
     kandarp 9 months ago

     in last step you can not directly do mirror...
     u should copy body for 90 degree + 17mm increment in z direction....

     is it true?

• 
  Mestrell 9 months ago

  Please explain how plane 3 was made in step 9.

  1. 
     Phil Kight 9 months ago

     I made a plane on the bottom of the cylinder, and than flipped that one to be perpendicular to the side where the water canal is located.

  2. 
     Mestrell 9 months ago

     Is there any way you could show this?

• 
  kandarp 9 months ago

  phil kight ,as per my method

  1. Step 1

     " U " section of lag 15mm make some blank space between chanal & cylinder surface.....(view fron bottom of cylinder)

     so i use " C " section of same dimention & sweep it at all around 6 cylinders & in other step extrud rectangle of " c " section's flat surface & extrude up to next surface...(as step 7).....

     after doing all this finaly u will get....

     

  2. Step 2

     in 3D

     

  1. 
     kandarp 9 months ago

     no ,
     there is a nathing interference between chanal & holes...
     because i did extrude up to next surface only.

  2. 
     Phil Kight 9 months ago

     kandarp, does the water channel still interfere with the head bolt holes? I've redesigned the water channel so that no extrusion cut needs to be done.

  3. 
     kandarp 9 months ago

     this is section view of cylinder 1...

• 
  Chanson 9 months ago

  Very impressive series and detailed deconstruction.

  Next time, please cite your sources if you would like to use my work, especially since it is a stipulation specified in the challenge rules.

• 
  Evandro Gaio 9 months ago

  Anyone can help me? Mirror about what? In 13st step . I try about every planes and try create a new planes to but still wrong. Ty

  1. 
     Evandro Gaio 9 months ago

     nvm I did

• 
  Cullen Williams 9 months ago

  Hey,
  I need to know how far exactly is the 2 cylinder blocks are from each other.. When I started drafting them, I think my dimensions were wrong so I had to move them to an approximate distance. Can you take a look at the picture I posted to let me know what that dimension is?

  Thanks,
  Cullen

  Added images

  

  1. 
     Kong 6 months ago

     The dimension was determined at step 1 and step 2 of tutorial part 10. I ended up with a 53.74 mm distance as the length of the red line you drew.

• 
  Brylle 8 months ago

  I think I'm in the same page with Cullen. I don't know how far these cylinders should be apart from eachother. Also I dont know if the method I used is correct. mirror the original body and use move/copy command. Need your help buddies. thank you

  Added images

  

  1. 
     Cullen Williams 8 months ago

     I made the dimension in your picture 50mm, or each cylinder block 25mm horizontally from the origin.

     Within the move/copy command there is an option of using the translate option. What I did was made a sketch on the front plane, that was basically 2 points for me to translate the bodies too. The bottom left corner of the block I made 87mm vertically above the origin, and 25mm horizontally from the origin. That will make the 2 cylinder blocks 50mm from each other after you mirror it about the right plane. Good Luck,

  2. 
     Brylle 8 months ago

     what you mean by block is a rectangle right? Also I still have no idea what translate command is. SW noob here. Can you show what you did? thanks buddy

• 
  hcortez 7 months ago

  In step 5, once you make these extruded cuts the coolant would then spray out the top and bottom of every cylinder. is this correct or??

  Also, not that its a big deal but you never show cleaning out the bolt holes because of the interferece from the water channels being added to the cylinders. Just a thought to help make it a more comprehensive tutorial for beginners like myself.

  One more thing; the yellow lines in step 9 are distracting to say the least, i wasnt picking up on the fact that these lines are just part of the actual preview process and not lines that are needed to make the sweep. Really making my brain work today!! Thanks again!!

  1. 
     Venus 6 months ago

     step 9 and 10 is not clear for me I'm still trying, If you have any comment?

• 
  Venus 6 months ago

  I couldn't do the sweep part step 9 and 10 anyone can help me?

• 
  hcortez 6 months ago

  Venus,

  I am attaching a picture from the above exercise. All you need for this sweep are the two black lines you see in the picture I have attached. So you will need the quarter round and the straight line, then try to sweep the feature.

  The "yellow lines" are confusing to say the least. They are just showing a preview of what will be done once the sweep is created.

  If this doesnt help I will revisit the exercise and give you better instructions!!

  Good Luck!!

  Added images

  

• 
  Süleyman Korkmaz 4 months ago

  ı cannot use mirror feature. what can ı do to use mirror properly

  mirror yapacağım zaman hata veriyor bana söylediği şu gövdeler kopuk olduğu için mirror yapılmıyor bu problemi nasıl çözebilirim

  1. 
     Aykut Dana 4 months ago

     selam, gövdeleri aynala seçeneğini kullanmalısınız ayrıca merge result kutusunu boş bırakın. olmazsa Crankcase karşılaştırma yapabilirsiniz

• 
  Pedro Sola 9 days ago

  The only step I did not understand is the step 5, can anyone explain it better, please?