Multi-Pitch Spring in SolidWorks

khalid

15 Nov, 2016 10:12 AM

In this tutorial I'll show how to create a closed end multi-pitch spring using SolidWorks 2014.

1. Step 1:

   Creating the base sketch:
   - Select the Front plane from the FeatureManager tree.
   - Click new Sketch.
   - Sketch a circle centered on the origin.
   - Add a diameter dimension of (1) unit length .
   

   

2. Step 2:

   Creating a helix using Variable Pitch:
   - Insert (Curve) Helix-Spiral.
   - Under Define By, select: Pitch and Revolution.
   - Under Parameter, select: Variable Pitch.
   - Under Region Parameters, enter the values for the Pitch, Revolutions, and Diameters.
   - Set Angle to (0) deg and Clockwise direction.
   

   

3. Step 3:

   Sketching the sweep profile :
   - Select the Top plane and open a new sketch .
   - Sketch a circle near the right end of the helix.
   - Add a Pierce relation between the center of the circle and the helix.
   

   

4. Step 4:

   Sweeping the profile along the path:
   - Insert (Bose-Base) Sweep.
   - Select the small circle for sweep profile .
   - Select the helix for sweep path .
   -Click OK ·
   

   

5. Step 5:

   Creating a trimmed sketch:
   - Select the Top plane from the Feature Manager tree and open a new sketch.
   - Sketch a rectangle and add a Midpoint relation between the line on top and the origin.
   - Add a width and a height dimension.

   

6. Step 6:

   Extruding a cut:
   - Insert(Cut) Extrude.
   - Set the Direction Through All Both.
   - Enable the Flip Side to Cut checkbox.
   - Click OK.