Wrap text to surface and then fill it with another part (Solidworks)
Hi! First time making a question in here so sorry for any mistake..
I'm new to solidworks, and i'm trying to engrave some text on a surface. I use the wrap command and i managed to accomplish that. But now i want to create another part were i fill those letters. Creating at the end two svg files: the main one and the lettering.
I did a lot of research and i can't manage to do that. Also read something about the split line command, but i couldn't boss extrude or extruded cut.
IMAGE: https://imgur.com/a/2qJyBQ6
Hope you can help me.
Thank you in adavance.
1 Answer
Hi Pedro,
This is easy to do as a multi-body part with the boolean features (subtract, add, combine etc). If you want separate part files, you can do that after creating the geometry in a multi body part. Here's how...
First, scroll the model tree back one, just before the 'wrap1' feature.
Then 'insert>feature>move/copy', select the existing part body, make sure the 'copy' option is checked and make only 1 copy. This will create an exact duplicate of the existing solid geometry. Don't translate or rotate, they should overlap. You should also see a new folder called 'Solid Bodies(2)' at the top of the model tree when finished. Go ahead and expand this folder and noticed the 2 separate solid bodies.
Now scroll the model tree back to the end, you should see two solid bodies, one with text and one without.
Next, 'insert>feature>move/copy' once again making sure to select the body that has the lettering to create a duplicate of that geometry. This is easiest to do from the model tree, in the "solid bodies" folder. When that's done, you should see 'Solid Bodies(3)', one of them being blank and the other 2 with the lettering.
Finally, 'insert>feature>combine', select the 'subtract' operation type, select the blank solid (no lettering) as the 'Main Body', and select one of the solids with the lettering as the 'Bodies to Subtract'. As you finish this command, the system will prompt you for "Bodies to Keep", select 'All bodies'.
Now you should have 12 solid bodies in the solid bodies folder. One for the main part, and 11 for the filled in lettering. You can 'hide' the main body to just see the lettering if you like.
You now have a multi-body part that can be used as is, or used to generate downstream parts if you need to have the main part separate from the lettering.
Create new downstream parts by EITHER creating empty parts and using 'insert part' to bring in the multibody part and 'delete body' to remove the unwanted geometry, OR by selecting the appropriate bodies in the model tree of the multi body part, right clicking and choosing 'insert into new part'.
That should get you close to what I think you're trying to do.
As always, there's more than one way to skin a cat, so someone might come by with a slicker method, but I like the booleans, and being familiar with adding/subtracting/combining geometry is super important when doing more advanced 'top down' modeling.
